| Author |
Message |
dakeb
Guest
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 Posted:
Wed Oct 06, 2004 7:07 pm Post subject:
cente line in sweep |
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If I generate a swept groove along a datum curve, and in the drawing show a
section cut through the groove, how do I show a vertical centre line to
dimension to?
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Jeff Howard
Guest
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| Posted:
Wed Oct 06, 2004 8:28 pm Post subject:
Re: cente line in sweep |
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| Quote: | If I generate a swept groove along a datum curve,
and in the drawing show a section cut through the
groove, how do I show a vertical centre line to
dimension to?
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I'm not picturing what you want, but when all else fails I'll put a datum
axis in the section plane to serve the purpose. |
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David Janes
Guest
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| Posted:
Thu Oct 07, 2004 5:56 am Post subject:
Re: cente line in sweep |
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: "dakeb" <david.bower@uk.thalesssssssspamgroup.com> wrote
: If I generate a swept groove along a datum curve, and in the drawing show a
: section cut through the groove, how do I show a vertical centre line to
: dimension to?
:
Why can't you use the curve trajectory as a dimensioning reference. If you'd
planned it so that the curve would be the center of the sweep cross section, you
could dimension to the center using the curve. As to 'showing' center lines, Pro/e
doesn't. It only shows the axis symbol. But, only cylindrical geometry creates
axes.
You might also consider putting a point on the curve, creating your sectioning
datum as thru point and normal to the curve. Then you'd at least have the point as
a 'for certain' dimensioning reference.
Don't know how the axis point works and can't even confirm that it does, never
been able to get it to work. Must be some very particular circumstance where it
will create and show an axis. But, what the hell, worth a try.
David Janes
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Randy Jones
Guest
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| Posted:
Thu Oct 07, 2004 6:33 am Post subject:
Re: cente line in sweep |
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David Janes wrote:
| Quote: | : "dakeb" <david.bower@uk.thalesssssssspamgroup.com> wrote
: If I generate a swept groove along a datum curve, and in the drawing show a
: section cut through the groove, how do I show a vertical centre line to
: dimension to?
:
Why can't you use the curve trajectory as a dimensioning reference. If you'd
planned it so that the curve would be the center of the sweep cross section, you
could dimension to the center using the curve. As to 'showing' center lines, Pro/e
doesn't. It only shows the axis symbol. But, only cylindrical geometry creates
axes.
You might also consider putting a point on the curve, creating your sectioning
datum as thru point and normal to the curve. Then you'd at least have the point as
a 'for certain' dimensioning reference.
Don't know how the axis point works and can't even confirm that it does, never
been able to get it to work. Must be some very particular circumstance where it
will create and show an axis. But, what the hell, worth a try.
As far as I know an axis point will create an axis only for an extruded |
feature.
--
----------------------------------
Randy Jones
E-Mail: randy@jones.tri.net
---------------------------------- |
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dakeb
Guest
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| Posted:
Thu Oct 07, 2004 2:40 pm Post subject:
Re: cente line in sweep |
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| Quote: | As far as I know an axis point will create an axis only for an extruded
feature.
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True that option is greyed out anyway. |
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dakeb
Guest
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| Posted:
Thu Oct 07, 2004 2:48 pm Post subject:
Re: cente line in sweep |
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"David Janes" <djanes@cox.net.invallud> wrote in message
news:Mn19d.259$cJ3.141@fed1read06...
| Quote: | : "dakeb" <david.bower@uk.thalesssssssspamgroup.com> wrote
: If I generate a swept groove along a datum curve, and in the drawing
show a
: section cut through the groove, how do I show a vertical centre line to
: dimension to?
:
Why can't you use the curve trajectory as a dimensioning reference. If
you'd
planned it so that the curve would be the center of the sweep cross
section, you
could dimension to the center using the curve.
|
I have done that, and can dimension to the datum curve (with c/l font) in
sections and elevations. Trouble is in section, the dimension line goes to
thin air (datum curves are pretty much invisible in section).
As to 'showing' center lines, Pro/e
| Quote: | doesn't. It only shows the axis symbol. But, only cylindrical geometry
creates
axes.
You might also consider putting a point on the curve, creating your
sectioning
datum as thru point and normal to the curve. Then you'd at least have the
point as
a 'for certain' dimensioning reference.
Don't know how the axis point works and can't even confirm that it does,
never
been able to get it to work. Must be some very particular circumstance
where it
will create and show an axis. But, what the hell, worth a try.
|
Nah, axis point option is greyed out in sketched curve.
Okay, here is a fudged solution:-
At the point where the section plane cuts through the groove, create a cut
feature, a round hole smaller than the width and depth of the groove, so
it's invisible (cutting thru space). The axis for this hole shows up in the
section. |
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David Janes
Guest
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| Posted:
Thu Oct 07, 2004 3:40 pm Post subject:
Re: cente line in sweep |
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"dakeb" <david.bower@uk.thalesssssssspamgroup.com> wrote in message
news:ck36u9$soh$1@rdel.co.uk...
:
: "David Janes" <djanes@cox.net.invallud> wrote in message
: news:Mn19d.259$cJ3.141@fed1read06...
: > : "dakeb" <david.bower@uk.thalesssssssspamgroup.com> wrote
: > : If I generate a swept groove along a datum curve, and in the drawing
: show a
: > : section cut through the groove, how do I show a vertical centre line to
: > : dimension to?
: > :
: > Why can't you use the curve trajectory as a dimensioning reference. If
: you'd
: > planned it so that the curve would be the center of the sweep cross
: section, you
: > could dimension to the center using the curve.
:
: I have done that, and can dimension to the datum curve (with c/l font) in
: sections and elevations. Trouble is in section, the dimension line goes to
: thin air (datum curves are pretty much invisible in section).
:
: As to 'showing' center lines, Pro/e
: > doesn't. It only shows the axis symbol. But, only cylindrical geometry
: creates
: > axes.
: >
: > You might also consider putting a point on the curve, creating your
: sectioning
: > datum as thru point and normal to the curve. Then you'd at least have the
: point as
: > a 'for certain' dimensioning reference.
: >
: > Don't know how the axis point works and can't even confirm that it does,
: never
: > been able to get it to work. Must be some very particular circumstance
: where it
: > will create and show an axis. But, what the hell, worth a try.
:
: Nah, axis point option is greyed out in sketched curve.
:
: Okay, here is a fudged solution:-
:
: At the point where the section plane cuts through the groove, create a cut
: feature, a round hole smaller than the width and depth of the groove, so
: it's invisible (cutting thru space). The axis for this hole shows up in the
: section.
:
What keeps it 'locked' to the groove? Will it follow the groove if the trajectory
changes? The biggest problem I've seen with kludged fixes is that someone else
comes along and has to figure out what a pointless hole is for. Hopefully,
*you'll* remember a year from now.
David Janes
: |
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Jeff Howard
Guest
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| Posted:
Thu Oct 07, 2004 4:29 pm Post subject:
Re: cente line in sweep |
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| Quote: | Okay, here is a fudged solution:-
At the point where the section plane cuts through the groove, create a
cut
feature, a round hole smaller than the width and depth of the groove, so
it's invisible (cutting thru space). The axis for this hole shows up in
the
section.
|
You want to dimension to (the point) where the trajectory intersects the
section plane? Point at intersection; Axis on point, normal to plane? |
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dakeb
Guest
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| Posted:
Thu Oct 07, 2004 4:50 pm Post subject:
Re: cente line in sweep |
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"Jeff Howard" <jeff4136@mindspring.com> wrote in message
news:MEa9d.5035$UP1.2160@newsread1.news.pas.earthlink.net...
| Quote: |
Okay, here is a fudged solution:-
At the point where the section plane cuts through the groove, create a
cut
feature, a round hole smaller than the width and depth of the groove, so
it's invisible (cutting thru space). The axis for this hole shows up in
the
section.
You want to dimension to (the point) where the trajectory intersects the
section plane? Point at intersection; Axis on point, normal to plane?
|
umm yeah, but thats two features, whereas a cut is just one. |
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dakeb
Guest
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| Posted:
Thu Oct 07, 2004 4:54 pm Post subject:
Re: cente line in sweep |
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"David Janes" <djanes@cox.net.invallud> wrote in message
news:qX99d.823$cJ3.305@fed1read06...
| Quote: | "dakeb" <david.bower@uk.thalesssssssspamgroup.com> wrote in message
news:ck36u9$soh$1@rdel.co.uk...
:
: "David Janes" <djanes@cox.net.invallud> wrote in message
: news:Mn19d.259$cJ3.141@fed1read06...
: > : "dakeb" <david.bower@uk.thalesssssssspamgroup.com> wrote
: > : If I generate a swept groove along a datum curve, and in the drawing
: show a
: > : section cut through the groove, how do I show a vertical centre line
to
: > : dimension to?
: > :
: > Why can't you use the curve trajectory as a dimensioning reference. If
: you'd
: > planned it so that the curve would be the center of the sweep cross
: section, you
: > could dimension to the center using the curve.
:
: I have done that, and can dimension to the datum curve (with c/l font)
in
: sections and elevations. Trouble is in section, the dimension line goes
to
: thin air (datum curves are pretty much invisible in section).
:
: As to 'showing' center lines, Pro/e
: > doesn't. It only shows the axis symbol. But, only cylindrical geometry
: creates
: > axes.
:
: > You might also consider putting a point on the curve, creating your
: sectioning
: > datum as thru point and normal to the curve. Then you'd at least have
the
: point as
: > a 'for certain' dimensioning reference.
:
: > Don't know how the axis point works and can't even confirm that it
does,
: never
: > been able to get it to work. Must be some very particular circumstance
: where it
: > will create and show an axis. But, what the hell, worth a try.
:
: Nah, axis point option is greyed out in sketched curve.
:
: Okay, here is a fudged solution:-
:
: At the point where the section plane cuts through the groove, create a
cut
: feature, a round hole smaller than the width and depth of the groove, so
: it's invisible (cutting thru space). The axis for this hole shows up in
the
: section.
:
What keeps it 'locked' to the groove? Will it follow the groove if the
trajectory
changes? The biggest problem I've seen with kludged fixes is that someone
else
comes along and has to figure out what a pointless hole is for. Hopefully,
*you'll* remember a year from now.
|
Sure, but then chances are the section plane will have to change too so all
bets are off. Proe can't do it so I have to fudge it.
Anyhow, it will follow the groove seeing as the curve that is the groove
trajectory is the reference for the centre of the cut hole. And I could even
use the hole axis as a location for the section plane. |
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Jeff Howard
Guest
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| Posted:
Thu Oct 07, 2004 5:23 pm Post subject:
Re: cente line in sweep |
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| Quote: |
umm yeah, but thats two features, whereas a cut is just one.
|
.... which can be created faster than the cut (don't even have to switch to
the part window if you have the curve and plane visible in a drawing view)
and will probably not cause any head scratching later on? If you like it,
though, .... 8~) |
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dakeb
Guest
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| Posted:
Thu Oct 07, 2004 7:02 pm Post subject:
Re: cente line in sweep |
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"Jeff Howard" <jeff4136@mindspring.com> wrote in message
news:srb9d.8428$M05.7997@newsread3.news.pas.earthlink.net...
| Quote: |
umm yeah, but thats two features, whereas a cut is just one.
... which can be created faster than the cut (don't even have to switch to
the part window if you have the curve and plane visible in a drawing view)
and will probably not cause any head scratching later on? If you like it,
though, .... 8~)
|
Creating the point is a bit tricky. You first have to create a datum plane,
and then place a point on the curve offset from the datum plane. So that is
a third feature. However the same datum plane can be used by the cross
section, instead of creating one on the fly. It's probably a better solution
as it doesn't use extraneous 'solid' features like cuts. |
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David Janes
Guest
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| Posted:
Fri Oct 08, 2004 7:10 am Post subject:
Re: cente line in sweep |
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"dakeb" <david.bower@uk.thalesssssssspamgroup.com> wrote in message
news:ck3lq1$f5q$1@rdel.co.uk...
:
: "Jeff Howard" <jeff4136@mindspring.com> wrote in message
: news:srb9d.8428$M05.7997@newsread3.news.pas.earthlink.net...
: > >
: > > umm yeah, but thats two features, whereas a cut is just one.
: > >
: >
: > ... which can be created faster than the cut (don't even have to switch to
: > the part window if you have the curve and plane visible in a drawing view)
: > and will probably not cause any head scratching later on? If you like it,
: > though, .... 8~)
:
: Creating the point is a bit tricky. You first have to create a datum plane,
: and then place a point on the curve offset from the datum plane.
No, as I said before, you first create the point 'on curve', 'length ratio' (this
allows you to create the point absolutely *anywhere* on your curve trajectory,
giving you perfect control over where to show your cross section). Then create a
datum plane 'thru point' and normal to the curve (as Jeff suggested). Then create
an axis 'thru point', 'normal plane' (which, in this case, will be your section
plane, so the axis will definitely show in your cross section). Then, create your
section geometry (in the model, of course), using the given axis as a reference.
Dimension the section (probably reference, since all these references are, after
all, just for reference and don't control anything since this is done by the
trajectory curve) and you will get your axis cross from the datum axis.
David Janes
So that is
: a third feature. However the same datum plane can be used by the cross
: section, instead of creating one on the fly. It's probably a better solution
: as it doesn't use extraneous 'solid' features like cuts.
:
: |
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dakeb
Guest
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| Posted:
Fri Oct 08, 2004 11:46 am Post subject:
Re: cente line in sweep |
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"David Janes" <djanes@cox.net.invallud> wrote in message
news:Tyn9d.1053$cJ3.257@fed1read06...
| Quote: |
"dakeb" <david.bower@uk.thalesssssssspamgroup.com> wrote in message
news:ck3lq1$f5q$1@rdel.co.uk...
:
: "Jeff Howard" <jeff4136@mindspring.com> wrote in message
: news:srb9d.8428$M05.7997@newsread3.news.pas.earthlink.net...
:
: > > umm yeah, but thats two features, whereas a cut is just one.
:
:
: > ... which can be created faster than the cut (don't even have to
switch to
: > the part window if you have the curve and plane visible in a drawing
view)
: > and will probably not cause any head scratching later on? If you like
it,
: > though, .... 8~)
:
: Creating the point is a bit tricky. You first have to create a datum
plane,
: and then place a point on the curve offset from the datum plane.
No, as I said before, you first create the point 'on curve', 'length
ratio' (this
allows you to create the point absolutely *anywhere* on your curve
trajectory,
giving you perfect control over where to show your cross section). Then
create a
datum plane 'thru point' and normal to the curve (as Jeff suggested). Then
create
an axis 'thru point', 'normal plane' (which, in this case, will be your
section
plane, so the axis will definitely show in your cross section). Then,
create your
section geometry (in the model, of course), using the given axis as a
reference.
Dimension the section (probably reference, since all these references are,
after
all, just for reference and don't control anything since this is done by
the
trajectory curve) and you will get your axis cross from the datum axis.
|
Thanks David. The reason I don't like the length ratio option much is
because it's a bit of a trial and error to get your point exactly on the
curve where you want your secton plane to be. If you make the point offset
from a datum plane, you can set the offset offset dimension to zero and get
it exactly where you want it. |
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