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Jason L ©
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 Posted:
Mon Sep 26, 2005 8:10 pm Post subject:
Radial Axis disappears when grouped! |
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Ok...anyone have a fix for this? I have a drawing that shows my radial
pattern with the bolt circle axis just fine. When I add the hole pattern to
a group, the radial axis disappears on the drawing but leaves the dimension
to the bolt circle diameter. HELP!!!! ( i am using Wildfire 2.0 )
Thanks in advance,
Jason
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David Janes
Guest
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| Posted:
Sun Oct 02, 2005 4:10 pm Post subject:
Re: Radial Axis disappears when grouped! |
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| Quote: | "Jason L ©" <tectranbrake@yahoo.com> wrote
Ok...anyone have a fix for this? I have a drawing that shows my radial
pattern with the bolt circle axis just fine. When I add the hole pattern to
a group, the radial axis disappears on the drawing but leaves the dimension
to the bolt circle diameter. HELP!!!! ( i am using Wildfire 2.0 )
|
Don't know why the circle axis would disappear in a drawing by adding the pattern to a group. I've done this before in earlier versions and the axis circle showed up fine. First thing I'd do, in the drawing, is make sure it isn't still there and just got turned off, not regenerating. I'd do all the usual stuff: 'Edit>Regenerate>Draft', check the layers to make sure it didn't get placed on a hidden one, then I'd do 'Show and Erase', pick the axis icon and show 'By View' or do 'Show all'. Then I'd do the really strange things, like messing with the system colors which can be used to 'hide' (they're there, you just can't see them, until you move your cursor over them and they highlight red, so you know they're there). And then, one last really goofy thing because you never know when Pro/GOOFY will strike (the internal joke module of Pro/e) is to check the detail options file (*.dtl) to make sure radial_pattern_axis_circle is still set to YES. Never know when the system will decide to load the wrong options file or someone on the network will try to 'fix' something.
--
David Janes |
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Jason L ©
Guest
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| Posted:
Mon Oct 03, 2005 4:10 pm Post subject:
Re: Radial Axis disappears when grouped! |
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David,
Does it matter if the hole was created using diameter rather than radius?
"David Janes" <djanes@cox.net.inseliges> wrote in message news:UqS%e.85689$DW1.81838@fed1read06...
| Quote: | "Jason L ©" <tectranbrake@yahoo.com> wrote
Ok...anyone have a fix for this? I have a drawing that shows my radial
pattern with the bolt circle axis just fine. When I add the hole pattern to
a group, the radial axis disappears on the drawing but leaves the dimension
to the bolt circle diameter. HELP!!!! ( i am using Wildfire 2.0 )
|
Don't know why the circle axis would disappear in a drawing by adding the pattern to a group. I've done this before in earlier versions and the axis circle showed up fine. First thing I'd do, in the drawing, is make sure it isn't still there and just got turned off, not regenerating. I'd do all the usual stuff: 'Edit>Regenerate>Draft', check the layers to make sure it didn't get placed on a hidden one, then I'd do 'Show and Erase', pick the axis icon and show 'By View' or do 'Show all'. Then I'd do the really strange things, like messing with the system colors which can be used to 'hide' (they're there, you just can't see them, until you move your cursor over them and they highlight red, so you know they're there). And then, one last really goofy thing because you never know when Pro/GOOFY will strike (the internal joke module of Pro/e) is to check the detail options file (*.dtl) to make sure radial_pattern_axis_circle is still set to YES. Never know when the system will decide to load the wrong options file or someone on the network will try to 'fix' something.
--
David Janes
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David Janes
Guest
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| Posted:
Tue Oct 04, 2005 5:56 am Post subject:
Re: Radial Axis disappears when grouped! |
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It shouldn't. It's the same axis circle, just a different dimensioning scheme. I've never seen it make any difference. In any case, I always use diametral and have never had this particular problem.
Should be easy enough to find out; just do 'Edit>Definition' and change it to radial or switch it back and forth, see if it makes a difference in the display of the 'radial' axis circle. But when I've had trouble with this, it's usually been one of the things I mentioned in my troubleshooting suggestions, especially the one about a detail file getting changed so that radial_pattern_axis_circle got set to NO. The other thing I've seen a problem with is people thinking that a hole, referenced to and, patterned on a pivoting datum, should produce the axis circle. However, only a hole that starts out with position type of radial/diametral, then patterned, can have this axis circle.
--
David Janes
"Jason L ©" <tectranbrake@yahoo.com> wrote in message news:fJb0f.6666$Ge5.2506@fe10.lga...
David,
Does it matter if the hole was created using diameter rather than radius?
"David Janes" <djanes@cox.net.inseliges> wrote in message news:UqS%e.85689$DW1.81838@fed1read06...
| Quote: | "Jason L ©" <tectranbrake@yahoo.com> wrote
Ok...anyone have a fix for this? I have a drawing that shows my radial
pattern with the bolt circle axis just fine. When I add the hole pattern to
a group, the radial axis disappears on the drawing but leaves the dimension
to the bolt circle diameter. HELP!!!! ( i am using Wildfire 2.0 )
|
Don't know why the circle axis would disappear in a drawing by adding the pattern to a group. I've done this before in earlier versions and the axis circle showed up fine. First thing I'd do, in the drawing, is make sure it isn't still there and just got turned off, not regenerating. I'd do all the usual stuff: 'Edit>Regenerate>Draft', check the layers to make sure it didn't get placed on a hidden one, then I'd do 'Show and Erase', pick the axis icon and show 'By View' or do 'Show all'. Then I'd do the really strange things, like messing with the system colors which can be used to 'hide' (they're there, you just can't see them, until you move your cursor over them and they highlight red, so you know they're there). And then, one last really goofy thing because you never know when Pro/GOOFY will strike (the internal joke module of Pro/e) is to check the detail options file (*.dtl) to make sure radial_pattern_axis_circle is still set to YES. Never know when the system will decide to load the wrong options file or someone on the network will try to 'fix' something.
--
David Janes |
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Jason L ©
Guest
|
| Posted:
Tue Oct 04, 2005 4:10 pm Post subject:
Re: Radial Axis disappears when grouped! |
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also the radial axis doesn't show up when you only have one hole located diametrically (not in a group). It shows up on the part but not the drawing. radial_pattern_axis_circle is set to yes. When it is patterned the circle shows up. This is driving me crazy!
"David Janes" <djanes@cox.net.inseliges> wrote in message news:Zrk0f.251$fE5.128@fed1read06...
It shouldn't. It's the same axis circle, just a different dimensioning scheme. I've never seen it make any difference. In any case, I always use diametral and have never had this particular problem.
Should be easy enough to find out; just do 'Edit>Definition' and change it to radial or switch it back and forth, see if it makes a difference in the display of the 'radial' axis circle. But when I've had trouble with this, it's usually been one of the things I mentioned in my troubleshooting suggestions, especially the one about a detail file getting changed so that radial_pattern_axis_circle got set to NO. The other thing I've seen a problem with is people thinking that a hole, referenced to and, patterned on a pivoting datum, should produce the axis circle. However, only a hole that starts out with position type of radial/diametral, then patterned, can have this axis circle.
--
David Janes
"Jason L ©" <tectranbrake@yahoo.com> wrote in message news:fJb0f.6666$Ge5.2506@fe10.lga...
David,
Does it matter if the hole was created using diameter rather than radius?
"David Janes" <djanes@cox.net.inseliges> wrote in message news:UqS%e.85689$DW1.81838@fed1read06...
| Quote: | "Jason L ©" <tectranbrake@yahoo.com> wrote
Ok...anyone have a fix for this? I have a drawing that shows my radial
pattern with the bolt circle axis just fine. When I add the hole pattern to
a group, the radial axis disappears on the drawing but leaves the dimension
to the bolt circle diameter. HELP!!!! ( i am using Wildfire 2.0 )
|
Don't know why the circle axis would disappear in a drawing by adding the pattern to a group. I've done this before in earlier versions and the axis circle showed up fine. First thing I'd do, in the drawing, is make sure it isn't still there and just got turned off, not regenerating. I'd do all the usual stuff: 'Edit>Regenerate>Draft', check the layers to make sure it didn't get placed on a hidden one, then I'd do 'Show and Erase', pick the axis icon and show 'By View' or do 'Show all'. Then I'd do the really strange things, like messing with the system colors which can be used to 'hide' (they're there, you just can't see them, until you move your cursor over them and they highlight red, so you know they're there). And then, one last really goofy thing because you never know when Pro/GOOFY will strike (the internal joke module of Pro/e) is to check the detail options file (*.dtl) to make sure radial_pattern_axis_circle is still set to YES. Never know when the system will decide to load the wrong options file or someone on the network will try to 'fix' something.
--
David Janes |
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Jason L ©
Guest
|
| Posted:
Tue Oct 04, 2005 4:10 pm Post subject:
Re: Radial Axis disappears when grouped! |
|
|
I have double-checked everything you mentioned David. Do you have WF2? If
you do, please try this....pattern a hole diametrically. Then put the
pattern group along with some other features into one group. The axis circle
will disappear in the drawing when grouped.
I went back and used the old menu as well and selected by range the features
to be grouped. Interestingly enough I got a message saying it couldn't add
the patterns to the group, but it appears as if they were grouped anyway. I
really need to solve this because we have "casting" features and "machining"
features. That way we can use the same part for both the casting and
machining drawings. We then just simplify the represention on the casting
drawing to elliminate the machining group.
Thanks.
Jason
"David Janes" <djanes@cox.net.inseliges> wrote in message
news:Zrk0f.251$fE5.128@fed1read06...
It shouldn't. It's the same axis circle, just a different dimensioning
scheme. I've never seen it make any difference. In any case, I always use
diametral and have never had this particular problem.
Should be easy enough to find out; just do 'Edit>Definition' and change it
to radial or switch it back and forth, see if it makes a difference in the
display of the 'radial' axis circle. But when I've had trouble with this,
it's usually been one of the things I mentioned in my troubleshooting
suggestions, especially the one about a detail file getting changed so that
radial_pattern_axis_circle got set to NO. The other thing I've seen a
problem with is people thinking that a hole, referenced to and, patterned on
a pivoting datum, should produce the axis circle. However, only a hole that
starts out with position type of radial/diametral, then patterned, can have
this axis circle.
--
David Janes
"Jason L ©" <tectranbrake@yahoo.com> wrote in message
news:fJb0f.6666$Ge5.2506@fe10.lga...
David,
Does it matter if the hole was created using diameter rather than radius?
"David Janes" <djanes@cox.net.inseliges> wrote in message
news:UqS%e.85689$DW1.81838@fed1read06...
| Quote: | "Jason L ©" <tectranbrake@yahoo.com> wrote
Ok...anyone have a fix for this? I have a drawing that shows my radial
pattern with the bolt circle axis just fine. When I add the hole pattern
to
a group, the radial axis disappears on the drawing but leaves the
dimension
to the bolt circle diameter. HELP!!!! ( i am using Wildfire 2.0 )
|
Don't know why the circle axis would disappear in a drawing by adding the
pattern to a group. I've done this before in earlier versions and the axis
circle showed up fine. First thing I'd do, in the drawing, is make sure it
isn't still there and just got turned off, not regenerating. I'd do all the
usual stuff: 'Edit>Regenerate>Draft', check the layers to make sure it
didn't get placed on a hidden one, then I'd do 'Show and Erase', pick the
axis icon and show 'By View' or do 'Show all'. Then I'd do the really
strange things, like messing with the system colors which can be used to
'hide' (they're there, you just can't see them, until you move your cursor
over them and they highlight red, so you know they're there). And then, one
last really goofy thing because you never know when Pro/GOOFY will strike
(the internal joke module of Pro/e) is to check the detail options file
(*.dtl) to make sure radial_pattern_axis_circle is still set to YES. Never
know when the system will decide to load the wrong options file or someone
on the network will try to 'fix' something.
--
David Janes |
|
| Back to top |
|
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David Janes
Guest
|
| Posted:
Wed Oct 05, 2005 4:10 pm Post subject:
Re: Radial Axis disappears when grouped! |
|
|
"Jason L ©" <tectranbrake@yahoo.com> wrote in message
news:Rbv0f.7114$Ge5.2493@fe10.lga...
| Quote: | I have double-checked everything you mentioned David. Do you have WF2? If you do,
please try this....pattern a hole diametrically. Then put the pattern group along
with some other features into one group. The axis circle will disappear in the
drawing when grouped.
I tried it as you suggested. Did a part from scratch with WF2, same results, |
radial axis circle on drawing disappeared (and reappeared as soon as I ungrouped
pilot hole, axis and radially patterned holes. In addition, the axes of the radial
holes changed orientation pointing to the center to plus signs. I suspect it's
changing something about the pattern (like turning it into a table pattern). The
axis circle is of the pattern, not of the radial hole however, the
radial/diametral dimension is of the location definition, not the pattern so it
stays.
| Quote: | I went back and used the old menu as well and selected by range the features to
be grouped. Interestingly enough I got a message saying it couldn't add the
patterns to the group, but it appears as if they were grouped anyway. I really
need to solve this because we have "casting" features and "machining" features.
That way we can use the same part for both the casting and machining drawings.
We then just simplify the represention on the casting drawing to elliminate the
machining group.
What to do is a big one, but don't see why NOT having the axis circle would keep |
you from proceeding as usual. As a work around, you could do a parametric sketch
in drawing mode, pick the center axis and a radial hole axis as snap references
and sketch your radial axis circle then change the line style to a dashed font. If
I get time, I'll put a call in to PTC tech support, see if they know what's going
on.
--
David Janes |
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| Back to top |
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Jason L ©
Guest
|
| Posted:
Fri Oct 07, 2005 8:10 pm Post subject:
Re: Radial Axis disappears when grouped! |
|
|
Thanks David,
At least its not my version thats just buggy. I did however remedy the
needed radial axis by doing the parametric sketch as you suggested and that
worked fine. Its just one more extra step, but at least I can get the job
done. If you hear anything from PTC, post it here or let me know. Thanks
again.
Jason
"David Janes" <djanes@cox.net.inseliges> wrote in message
news:NGP0f.364$fE5.135@fed1read06...
| Quote: | "Jason L ©" <tectranbrake@yahoo.com> wrote in message
news:Rbv0f.7114$Ge5.2493@fe10.lga...
I have double-checked everything you mentioned David. Do you have WF2? If
you do, please try this....pattern a hole diametrically. Then put the
pattern group along with some other features into one group. The axis
circle will disappear in the drawing when grouped.
I tried it as you suggested. Did a part from scratch with WF2, same
results, radial axis circle on drawing disappeared (and reappeared as soon
as I ungrouped pilot hole, axis and radially patterned holes. In addition,
the axes of the radial holes changed orientation pointing to the center to
plus signs. I suspect it's changing something about the pattern (like
turning it into a table pattern). The axis circle is of the pattern, not
of the radial hole however, the radial/diametral dimension is of the
location definition, not the pattern so it stays.
I went back and used the old menu as well and selected by range the
features to be grouped. Interestingly enough I got a message saying it
couldn't add the patterns to the group, but it appears as if they were
grouped anyway. I really need to solve this because we have "casting"
features and "machining" features. That way we can use the same part for
both the casting and machining drawings. We then just simplify the
represention on the casting drawing to elliminate the machining group.
What to do is a big one, but don't see why NOT having the axis circle
would keep you from proceeding as usual. As a work around, you could do a
parametric sketch in drawing mode, pick the center axis and a radial hole
axis as snap references and sketch your radial axis circle then change the
line style to a dashed font. If I get time, I'll put a call in to PTC tech
support, see if they know what's going on.
--
David Janes
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